About Views from Profile  

This topic provides more information on profile views in terms of the 2D profile, multi-plane section views, mono-plane section views, and auxiliary views. The following topics are discussed:

What Are Offset or Aligned Multi-Plane Section Views?

This sub-topic explains what offset or aligned multi-plane section views are.
A multi-plane section view is a section view that has multiple planes. It can be either:

  • An offset section view (with multiple planes parallel to each other).
  • An aligned section view (with multiple planes that are secant by pair).

In both examples shown above, the section view profile contains three segments. The red point is the origin of the first view, the blue point the origin of the second view and the green point the origin of the third view. These three points will be projected at the same position in the multi-plane section view, and this position will be the origin of the sub-views.

These sub-views contain the actual geometry and annotations created in the multi-plane section view (you cannot create geometry or annotations outside a sub-view).

Display of Sub-Views in the Specification Tree

By default, the sub-views are not displayed in the specification tree. The sub-views of sections created before V5-6R2017 (R27) release are displayed in the specification tree.

To display them, right-click a section view in the specification tree and select Properties. In the Properties dialog box, switch to Visualization tab and select Display sub-views in specification tree.

You can also select Tools > Options > Mechanical > 2D Layout for 3D Design > View Creation tab > Multi-planes Section View > Display sub-views in specification tree.
Tips:
  Right-click the section view and select Sub-views > Sub-view.x to perform the following operations:
  • Access the sub-view properties
  • Activate the sub-views (Not available for sub-views of monoplane section)
  • Edit or change the view filters
  • Display and resize boundaries
  • Display view plane in 3D
  • Display View Plane/Profile in 3D
  • Restore show state
  For a monoplane section view, right-click the view and select the subview to access the related properties.

Hide or Show Section View and its Sub-Views
  •  If a section view is in Show mode, the visibility of the sub-views depends on their individual Hide/Show status.
  • If a section view is in Hide mode, the sub-views are hidden irrespective of their individual Hide/Show status.

Sub-View Boundaries

This sub-topic makes miscellaneous remarks about multi-plane section views:

General Remarks about Sub-View Boundaries

Each sub-view has two boundaries corresponding to the segment end points of the clipping profile.
Take the following section, for example.

The resulting boundaries are the following:

Display of Sub-View Boundaries

By default, when the multi-plane view is created, the first boundary of the first sub-view and the last boundary of the last sub-view are hidden.


You can change this default behavior. From Tools > Options > Mechanical > 2D Layout for 3D Design > View Creation tab > Multi-planes Section View area, select Display all boundaries but extreme ones.

You can show or hide all the boundaries in a multi-plane section view, by right-clicking the view and selecting Section View object > Display Boundaries or Section View object > Mask Boundaries from the contextual menu.

You can also show or hide boundaries on a given sub-view, or on a selection of sub-views, by right-clicking the required sub-views and selecting View object > Display First Boundaries or View object > Mask Second Boundaries.

Note: The Hide/Show command has no effect on boundaries

Resize of Boundary Segments

You can shorten or extend the length of a boundary segment. To do so, select the boundary segment. Two manipulators are displayed at each end. Drag them to resize the boundary segments as wanted.

You can resize several boundary segments at once by multi-selecting them. In this case, pressing the Ctrl key while manipulating resizes all the boundaries to the same length.

You can also bring back the resized boundary length to the original default length, by right-clicking the view and selecting Section View object > Resize Boundaries On View Background.

 

3D Visualization

This sub-topic explains how the section view/cut and its sub-views can be displayed in 3D.

Display View in 3D

You can view the sub-views in 3D according to the 2DL section view.
Right-click the view and select 3D Visualization > Display View in 3D.

Display View Plane/Profile in 3D

You can now view all the sub-view planes in 3D according to the profile of 2DL section view.
Right-click the view and select 3D Visualization > Display View Plane/Profile in 3D.

Multi-Plane Section View and Sub-View Properties

This sub-topic deals with the properties of multi-plane section views and sub-views.
You can edit the properties of a multi-plane section view or sub-view by right-clicking it and selecting Properties. Only specific properties are detailed below.
The following are discussed:
 

Multi-Plane Section View Properties

In the Properties dialog box for multi-plane section views, the View tab and the Visualization tab offer options that are specific to multi-plane section views. For options that are not specific to multi-plane section views, refer to Editing View Properties.

View tab

  • Name: Specify the name of 2DL multi-plane section view.
  • Angle: Define the angle from the sheet horizontal axis for all the sub-views of the 2DL multi-plane section view.
  • Scale: Set the scale of all the sub-views of the 2DL multi-plane section view.
  • Display View Frame: Show/hide the sub-view frame.
  • Lock View: Lock the sub-view so that it cannot be modified.
You cannot edit the position, scale and rotation of sub-views. They are modified by editing the multi-plane view properties.


Visualization tab

  • Display all boundaries: Select this option to display all the boundaries in the sub-views.
  • Color: Choose the color of the boundaries. By default, it is white.
  • Line type: Choose the line type of the boundaries. By default, it is 4.
  • Thickness: Choose the thickness of the boundaries. By default, it is 1.

Multi-Plane Section Sub-View Properties

In the Properties dialog box for multi-plane section views, the Visualization tab offers options that are specific to multi-plane section sub-views. Other tabs offer no specific options and are detailed in Editing View Properties.

  • Filter: Select the name of the filter applied to the sub-view.
    Note: Only display filters can be applied to sub-views.
  • Boundaries: Select the boundaries to be displayed in the sub-view.

Miscellaneous Remarks About Section Views

This sub-topic makes miscellaneous remarks about multi-plane section views.
  • Section views appear in the specification tree, at the same level as other types of views. They can be reordered as any other view.
  • The sub-views cannot be reordered. Their order depends on the order of section profile segments.
  • You can lock each sub-view of a multi-plane section view, but not the multi-plane section view itself.
  • There is one global view frame for the entire section view enveloping all its sub-views. You can show or hide this from view properties. Right-click a view and select Properties. In the View tab of the Properties dialog box, select the Display View Frame check box.
  • You can insert each sub-view of a multi-plane section view in a mask or display filter, but not the multi-plane section view itself.
    Note: Mask filter cannot be created in sub-views using the Filter > Layout View Filters, in the Layout View Filters dialog box.
  • The names of the section views and their sub-views are linked associatively.
  • To activate the first sub-view of the multi-plane section view, you can right-click the multi-plane section view and select Definition.
  • You cannot create new 2D Layout views from a multi-plane section view and its sub-views.
  • The following commands are not available for a multi-plane section view and its sub-views:
    • 2D Visualization mode
    • Rectangular/ Polygonal/Circular Clipping
    • Back-Clipping Plane

 

Modifiable Mono-Plane Section View

This sub-topic makes remarks about mono-plane section view.

  • If the section view profile consists of a single segment, the section view is a mono-plane section view.
  • The profile view is associated to the 2D profile. This is a default behavior. So when you modify the sketch of the section view, the view is modified accordingly.
  • You can:
    • Associate the profile view to the view
    • Isolate the profile view from its reference view
    • Change the profile view support
  • If the reference view is deleted, a warning message appears prompting that the associativity will be broken.
  • When a modifiable mono-plane section view is created, a sub view with a clipped background is created.
  • You can access the back clipping plane, 2D visualization mode, and the clipping frame from the the modifiable section view (and not the sub-view). To access them, open the contextual menu of the section view from the node in the specification tree.
  • In the specification tree, the symbol of a mono-plane section is masked with the following to denote special cases:
    • A red profile across the icon: if the view is created from a 2D profile
    • A lightning bolt: if the view is isolated from the plane or the 2D profile
 

Modifiable Auxiliary View

This sub-topic makes remarks about modifiable auxiliary view.

  • It is a view component whose 3D plane is decided by a single segment profile.
  • The profile view is associated to the 2D profile. This is a default behavior. So when you modify the sketch of the section view, the view is modified accordingly.
  • You can:
    • Associate the profile view to the view
    • Isolate the profile view from its reference view
    • Change the profile view support
  • You can access the back clipping plane, 2D visualization mode, and the clipping frame from the the modifiable section view (and not the sub-view).
  • If the reference view is deleted, a warning message appears prompting that the associativity will be broken.
  • In the specification tree, the symbol of an auxiliary view is masked with the following to denote special cases:
    • A red profile across the icon: if the view is created from a 2D profile
    • A lightning bolt: if the view is isolated from the plane or the 2D profile
    • No masking: if the view is created from a reference plane and is associative to it
  • You can invert the view direction.
 

Profiles Through Circular Geometry

This sub-topic makes remarks about profiles which pass through the circular geometry. According to the type of profile to be created, the detected constraints are different.

  • For an offset section view or cut
    • When the circle is selected before selecting the start point: A line passing through the center of the circle appears. You can click along this line to select the start and the end point of the segment of the profile
    • When two circles are selected consecutively before selecting the start point: A line passing through the centers of both the circles appears. You can click along this line to select the start and the end point of the segment of the profile.
    • When a circle is selected after selecting the start point: A line passing through the center of the circle and this point appears. You can click along this line to select end point of the segment of the profile.
    • When two circles are selected consecutively  after selecting the start point: The first and the middle segment are automatically created. You can select the end point to complete the section view or cut.
    • When at least two points of the profile are already selected and then a circle is selected consecutively: The first and the middle segment are automatically created. The third segment is partially created as a line passing through the center of the circle appears. You can select the end point to complete the profile
      .
  • For an aligned section view or cut
    • When the circle is selected before selecting the start point: A line passing through the center of the circle appears. You can click along this line to select the start point. The second point is automatically on the center of the circle. You can then select the third point, as required.
    • When two circles are selected consecutively before selecting the start point: A line passing through the centers of both the circles appears. You can click along this line to select the start point. The second point is automatically on the center of the second circle.
    • When a circle is selected after selecting the start point: The second point is automatically on the center of the circle.
 

About Modifying a Profile View

Manipulation in one direction according to the callout Manipulation in two directions according to the callout

For projection and mono-plane sections:

You cannot move one extremity beyond the other.
For projection and mono-plane sections:
For offset sections:

You cannot move an extremity beyond the folding line.		 For offset sections:
For aligned sections:

You cannot move an extremity beyond a folding point.		 For aligned sections:

When working with translation of the profile:
  • White square manipulators appear at the end of the segments.
  • You can only move the extremities along the support. You cannot change the support itself.
  • You can press the Ctrl key to move both the extremities together by the same distance. That is, if you move one extremity keeping the Ctrl key pressed, the other extremity moves in the opposite direction

When working with manipulation in two directions according to the callout, yellow diamond manipulators appear at the end of the segments. 



When working with manipulation in one direction or two directions according to the callout:
  • When you hover the pointer on a segment the pointer shows the rough direction of allowed movement or if there is no movement possible.
  • You can press the Shift key to snap the position of extremities or folding lines on the grid.