View Creation 

 

This page deals with the following categories of options in the View Creation tab:
 

View Visualization  
 

Hide in 3D

Select this check box if you want newly created views to be hidden from the 3D window.

  • You can show or hide the view in the 3D window at any time by right-clicking it in the 2D window and selecting Visualization  >  Show in 3D or Visualization  >  Hide in 3D respectively.
  • The hidden element is displayed in the specification tree with a masked icon.

By default, this check box is not selected.
 

View Background  
 

Display mode

From the drop-down list, select a display mode to specify how the 2D and 3D backgrounds should be visualized for newly created views:

  • Standard: shows both the 2D and 3D backgrounds.

  • Invisible: hides both the 2D background (the 3D representation of 2D elements which do not belong to the current view, but to other views) and the 3D background (the representation of all 3D elements, including edges, faces and 3D wireframe).

  • Unpickable: prevents selecting elements in both the 2D and 3D backgrounds, even though you can see them. You can just handle 2D elements which belong to the current view.

  • Low-intensified: dims all elements in both the 2D and 3D backgrounds.

  • Unpickable low-intensified: dims all elements in both the 2D and 3D backgrounds. Additionally, although you can see these elements, you cannot select them. You can just handle 2D elements in the current view.

By default, the Standard display mode is selected.
 

Activate 2D visualization mode

Select this check box if you want to display only the 2D planar elements that are in the same plane as this view in 3D for the newly created views.

By default, this option is not selected.
 

Filter  
  Select different options to set filter preferences for various views. The following filters are available:
  • No Filter: No filter is applied to the view.
  • Default Filter: The default filter is applied to the view.
  • Display Filter: A new display filter is created and applied to the view. The filter has the same name as the view, if possible, taking naming uniqueness into account.
  • Mask Filter: A new mask filter is created and applied to the view. The filter has the same name as the view, if possible, taking naming uniqueness into account.
  • List Filter: A list of available filters is displayed. You can choose an existing filter or create a new one.
  • Active View Filter: The same filter as the active view is applied.
  • Reference View Filter.

If a view is created with a 3D Tolerancing & Annotation capture as reference, a filter equivalent to the filter on the capture is applied. If a view is created with a 3D Tolerancing & Annotation section view or section cut (aligned or offset), as reference, a mask filter containing the annotation set and layout is applied.

The Display Edit Filter dialog box option is available if Display Filter or Mask Filter is selected. If selected, this option enables the edition of the filter at the end of the view creation.

By default, this option is selected.


Select the Populate filter based on selected reference for Section and Section Cut Views to add the set containing the selected reference to the created filter, if the reference is a geometric element in the current shape. It is only available when Display Filter is selected.

By default, this option is selected.
 

3D Grid
 
The following section is applicable for principal views, views from references, views from profiles, and axonometric views.
 

Display

Select this check box to display the 3D grid in the work area. If this check box is cleared, the classic grid view is visualized.

By default, this check box is selected.

From the list next to the Display check box, select the required Work On Support (WOS).

  • The list displays only the name of WOS 2D which are parallel to the view plane.
  • If you select multiple parallel views at the same time, the WOS 2D parallel to them are displayed.
  • The list directly shows the WOS 3D.
  • If you select multiple views associated to different WOS 2D which are part of a single WOS 3D, then that WOS 3D is directly selected.
  • If you apply a WOS 3D to multiple views, the selected views are associated with the first compatible WOS 2D of the selected WOS 3D.
 

Label position

There are four positions where you can display the labels of the grid:

  • Top
  • Bottom
  • Left
  • Right

By default, Bottom and Left are selected.
 

Font

You can select the font of the labels of the grid.

By default, no font is selected.
 

Size

You can select the font size of the labels of the grid.

By default, the font size is 3.5mm.
 

Reference

You can position the labels with reference to the following:

  • Sheet
  • View

By default, View is selected.
 

Grid Overrun

You can select the overrun of the grid. This decides the distance at which the grid will be placed from the 2D bounding box of the view.

By default, it is 10mm.
 

Automatic Grid Size

Select this check box to automatically select the grid size according to the size of the view. If this option is cleared, the grid size is modified as follows:

  • For an infinite work on support: Based on the size of the 3D background or the size of the view content.
  • For a finite work on support: Based on the size of the work on support.

By default, this check box is selected.
 

Clipping Frame  
 

Activate

Select this check box if you want to clip the 2D and 3D backgrounds of newly created views using a rectangular frame. Refer to Using the Clipping Frame for more information.

By default, this check box is not selected.
 

Clipping Outline  
 

Display

Select this check box if you want to display the outline of the clipping view. Refer to Using the Clipping View for more information.
 

  • Color: By default, white color is selected.
  • Line type (only among the first height linetypes): By default, type 4.
  • Thickness: By default, thickness is 1.

By default, this check box is selected.
 

Back Clipping Plane  
 

Activate

Select this check box if you want to clip the 2D and 3D backgrounds of newly created views using a back clipping plane. Refer to Using the Back-Clipping Plane for more information.

By default, this check box is not selected.
 

Primary View
 

Default offset between views


Enter the default offset between any two principle views created using the Principle Views command from the View Layout section of the action bar.

By default, the value is 10 mm.
 

When selecting a reference element: Change primary view plane

Select this check box if you want to change the principal view plane element during the view creation.

By default, this option is selected.

When selecting a reference element: Resize view box according to 3D model

Select this check box if you want to resize the view box once you have selected an element.

By default, this option is selected.

 

Manage 3D Grid label display


Select this check box to create no other label within the group of views created.

By default, this option is selected.

 

Multi-planes Section View Boundaries   

Display sub-views in specification tree

Select this check box to display the sub-views of a section view in tree.

By default, this check box is selected.

Display all boundaries but extremity ones

Select this check-box if you want all the boundaries in newly-created multi-plane section views to be displayed by default. Only the first and last boundary of the first and last sub-view respectively will not be displayed.

  • Color: By default, white color is selected.
  • Line type: By default, type 4.
  • Thickness: By default, index 1.

By default, this check box is selected.
 

View From Reference 
 

Reference perpendicular to active view

Align according to active view (SHIFT toggles)
Select one or both of the following options to align the newly created view to the active view:
  • Along folding direction
  • Perpendicular to folding direction

By default, these check boxes is selected.

  • The view can be moved either along the folding direction or perpendicularly to it. Both these directions are represented by two dashed lines.
  • The origin of the created view stays on the folding line containing its projection in the 3D background of the active view.
  • You can also modify the 3D definition of the view plane in the View Creation dialog box to update the position and orientation of the view and make it consistent with the active view.
The Shift key toggles the preference. That is, when the option is selected, then pressing the Shift key clears the selection. The view is no more aligned to the active view.
 

Reference non-perpendicular to active view

Align according to active view (SHIFT toggles)
Select one or both of the following options to align the newly created view to the active view:
  • Along folding direction
  • Perpendicular to folding direction

By default, these check boxes is selected.

  • The view can be moved either along the folding direction or perpendicularly to it. Both these directions are represented by two dashed lines.
  • The origin of the created view stays on the folding line containing its projection in the 3D background of the active view.
  • You can also modify the 3D definition of the view plane in the View Creation dialog box to update the position and orientation of the view and make it consistent with the active view.
The Shift key toggles the preference. That is, when the option is selected, then pressing the Shift key clears the selection. The view is no more aligned to the active view.
 

Set orientation according to the active view.

Select this check box to orient the newly created view to the active view. You can choose to select or clear this option when the Align according to active view (SHIFT toggles) option is selected.

By default, this check box is selected.
 

Create callout in active view

Select this check box to create callouts in active view at the end of View From Reference command.

This enables you to create a callout when creating an auxiliary view, a section cut or a section view (including multi-plane section views) from a 3D plane, face or sketch, using the New View From command.

  • If several section cut or section views are created at the same time, callouts are created for only those views whose support plane is normal to the support plane of the active view.
  • If the active view is not compatible for the callout creation, no callout is created. However, it is possible to add callouts in compatible views after the View From Reference command using the Create Callout in Reference View command. For more information, see 2D Layout for 3D Design User's Guide: Creating Callouts for Section/Auxiliary Views.
  • If you do not want the automatic callout creation, you can clear the Create callout in active view check box.

By default, this check box is selected.
 

 Activate created view

Select this check box to activate the created view at the end of the View From Reference command.

By default, this check box is cleared.
 

Propagate scale from active view

Select this check box to create a reference view with the same scale as the active view.

By default, this check box is cleared.
 

Callout Creation
 

Callout Size Overrun

Defines the overrun size of a callout.

By default, this value is 5.0mm.
 

Enable creation of callout for non-perpendicular view

When selected, this option allows creation of callout where the active view is not perpendicular to the reference plane. However, if the active view is parallel to the selected reference, the callout is not created, irrespective of this option.

By default, this check box is cleared.
 

Position callout of non-perpendicular view according to resulting view bounding box

When this check box is selected, it lets you to place the callout at the middle of the bounding box.
This check box is only available if the Enable creation of callout for non-perpendicular view check box is selected.

By default, this check box is selected.
 

View Layout
 

The following options customize various preferences when you create 2D Layout for 3D Design views directly from Functional Tolerancing and Annotations annotation sets, captures, or views.

For more information, see 2D Layout for 3D Design User's Guide : View Creation : Creating a Layout from Functional Tolerancing and Annotations.
 

Offset from sheet

Enter the offset at which the views are placed from the sheet.
By default, this value is 50.0 mm.
 

Offset between views

Enter the offset at which the views are placed from each other.
By default, this value is 30.0 mm.
 

Minimum Reduction Multiplier

Enter the lowest multiplier to which the view can be scaled down.
By default, the value is 0.500.
 

Maximum Enlargement Multiplier

Enter the highest multiplier to which the view can be scaled up.
By default, the value is 5.000.
 

Create Callout

Defines whether the callout must be automatically generated during view layout generation.

By default, this check box is selected.
 

Create View Text

When this check box is selected, it lets you create the view text during the view layout generation.

By default, this check box is selected.
 

View specification according to:

  • Tolerancing capture
  • Tolerancing view associated to tolerancing capture

Defines whether the capture specifications must be followed or the view specifications.

By default, the Tolerancing view associated to tolerancing capture check box is selected.
 

One View Per Sheet

When this check box is selected, only one view can be created in each sheet.

By default, this check box is cleared.
 

Fit to sheet size

Defines whether the scale of the view must be increased, so that the view bounding box is maximum to fit in the sheet size.

This check box is available only when the One view per sheet check box is selected.

By default, this check box is cleared.
 

Script for Frame and Title Block

This option is the name of the script (without the extension) which must be launched to create the frame and title block during the view layout generation.
This script file must be in the directory defined by the existing option directory for the frame and title block (defined in Background View section of the Layout tab in Drafting app).

By default, the value is Drawing_Titleblock_Sample1.
 

Delete Layout Views not Related to Tolerancing View or Capture

When this check box is selected, the views ignored during update are deleted.

By default, this check box is selected.