Administration for Drafting

 
 

This page deals with the following categories of options in the Administration tab:
 

Drawing management

 

Prevent File > New

Select this option to make it impossible to create drawings using the File > New command. All drawings will be created using the File > New From... command instead.

By default, this option is not selected.

Prevent switch of standard

Select this option to make it impossible to change standards, i.e. to use a standard other than the one currently defined in the Page Setup dialog box.

By default, this option is not selected.

Prevent update of standard

Select this option to make it impossible to update standards for the current document in the Page Setup dialog box.

By default, this option is not selected.

Prevent background view access

Select this option to make it impossible to access the background view.

By default, this option is not selected.

Prevent view geometry upgrade

Select this option to deactivate the Geometry Upgrade contextual command (used to upgrade sketched geometry in views) which is available for drawings, layouts, sheets and views.

By default, this option is selected.
 

Style

 

Default behaviors of property toolbars

The behavior of default value of an item in the property toolbars can be configured. The four families of property toolbars that support this are:

  • Text Properties toolbar
  • Dimension Properties toolbar
  • Numerical Properties toolbar
  • Graphical Properties toolbar

If you click the Configure button, the Default behavior of property toolbars dialog box appears.

The above properties can have the following configurations for default value:

  • Fix value: The default value is fixed irrespective of the current style in the Style toolbar, except when an element is being created or is selected. On changing the current style, the properties with fixed value remain unchanged.

    Notes:
     
    • The following properties do not have a fix value configuration:
      • Frame
      • Symbol
      • Dimension line
      • Numerical display description
    • When the behavior of a property is set to Fix value, the default values are not stored on closing the session.
    • When the behavior of a property is set to Fix value, the default values are applied for all objects supporting the considered property.
      The modifications in the graphic properties dialog box override the standard style and impact several features.
  • Value based on element type: The default value is stored by element type when the current style is changed in the Style toolbar, unless some elements are being created or are selected.
    The stored property values are restored each time a style of the same element type is set as current in the Style toolbar.
    Notes:
     
    • When the behavior of a property is set to Value based on element type, the default values are not stored on closing the session.
    • When switching to another element type, last overloaded values (default values) of this element type are restored to properties in such mode.
    • The Pattern property does not have the Value based on element type mode.
  • Value based on style: The property values are reset to style values each time a style corresponding to a new element type is set in the Style toolbar, unless some elements are being created or are selected. That is, each time a style is changed in the Style toolbar, the property default value is changed to fit the style property value.
    Notes:
     
    • For Value based on style mode, default values are automatically initialized to style values.
    • You can overload the default value before creation of an element. In this case, after creating the element, if you clear all selection, default value is restored.
  • Value based on style (No overload): The property values are reset to style values each time a style corresponding to a new element type is set in the Style toolbar. They cannot be modified unless some elements are being created or are selected.
    Notes:
     
    • For Value based on style (No overload) mode, default values are automatically initialized to style values.
    • You cannot overload the default value before creation of an element.

The Tolerance Description and Tolerance properties are mutually dependant. Updating one updates the other too.

For documents created with standards used before V5-R11, the styles are not applicable. For such documents, the Value based on element type or Value based on style behave like Fix value.

By default, the behavior of each property is Value based on style .
 

Use style values to create new objects

Select this option if you want dialog boxes, Properties toolbars and the Tools Palette to be pre-filled with custom style values (as defined in the Standards Editor) when creating new annotations. In this case, Properties toolbars and the Tools Palette will be disabled during the creation of the annotation.
If you leave this box unchecked, annotation dialog boxes, Properties toolbars and the Tools Palette will be pre-filled with the last entered values (except for Texts, Texts with leader, Balloons and Datum features). In this case, Properties toolbars and the Tools Palette will be active during the creation of the annotation.

If you select this option, you will be able to reset the current style values in dialog boxes at any time using the Reset button unless it is disabled.

By default, this option is not selected.
 

Create new sheet from (for pre-V5R14 drawings)

This option lets you specify if the properties used for creating new sheets should be those defined in the standards or those defined in the first sheet of a drawing. These properties are the scale and the projection method (first or third angle). 

Select Style if you want the sheet to use the style defined in the standards (in Tools > Standards > Drafting > [StandardName] > Styles > Sheet).

Select First sheet if you want the sheet to use the properties defined in the first sheet of a drawing. For example, you can use this option if you use an existing drawing to create a new one (i.e. when you want the new drawing to have the same properties as the existing drawing).

This option applies only to drawings created with versions prior to V5R14.

By default, First sheet is selected.
 

Lock "User Default" Style

Select this option to make it compulsory to use User Defaults (i.e., user-defined values set as default). The Styles drop-down list will be set to Only User Defaults and will be inactive so that Original Defaults or User Defaults cannot be selected.

This option applies only to drawings created with versions up to V5 R10 whose standard has NOT been updated or changed in V5 R11 and later.

By default, this option is not selected.

Prevent "Set As Default" and "Reset All Defaults"

Select this option to use the current defaults and to make it impossible to create, change and reset user defaults (i.e. user-defined values). This disables the Set as Default and the Reset All Defaults commands. 

This option applies only to drawings created with versions up to V5 R10 whose standard has NOT been updated or changed in V5 R11 and later.

By default, this option is not selected.
 

Display Reset button in dialog boxes

Display Reset button in dialog boxes Select this option to display the Reset button in dialog boxes. Clear this option to hide the Reset button in dialog boxes and to disable the Reset functionality. This option only concerns dialog boxes referring to annotations, dimensions, dress-up, 2D geometry.

By default, this option is selected.
 

Generative view style

 
 

Prevent generative view style usage

This option is used for the Generative Drafting workbench only.

Select this check-box if you do not want to use generative view styles when creating or updating views. In this case, you will not be able to select a generative view style after having selected a view creation command, which means that the Generative View Style toolbar will not be displayed. (In the case of advanced front views, it is the Generative view style list in the View Parameters dialog box which will not be displayed).

Note that this option also drives view generation parameters when updating views, whether the view was created using generative view styles or not. In this case, there are two possibilities:
  • If you created the view using generative view styles (i.e. with this check-box cleared) and then select this check-box, then, at the next update, the view properties (available via Edit > Properties) will be used for all overloaded parameters (an asterisk * appears in the Properties dialog box in front of the parameters which are considered as being overloaded) while other parameters will remain unset.
  • If you created the view without generative view styles (i.e. with this check-box selected) and then clear this check-box, then, at the next update, all parameters available in the view properties (available via Edit > Properties) will be considered as being overloaded and will be used. To make sure that generative view styles are used in this case, click the Reset to style values button in the Properties dialog box.

 

If you deactivate the Prevent generative view style usage option in Tools > Options > Mechanical Design > Drafting > Administration, Generative view style field, then the 3D colors option is not available in the view properties any more.

For more information, refer to the Generative View Styles chapter in the Generative Drafting User's Guide.

By default, this option is selected.
 

Dress-up

 
 

Prevent dimensions from driving 3D constraints

Select this option to make it impossible to modify a 3D constraint via a 2D dimension that was generated from it.

By default, this option is selected.
 

Naming Uniqueness
 
 

Ensure uniqueness of sheet names
  Select this check box to ensure the uniqueness of sheet names during creation or renaming.
  By default, this check box is cleared.
 

Ensure uniqueness of view names

  Select this check box to ensure the uniqueness of view names during creation or renaming.
  By default, this check box is cleared.

In sheet

Check the uniqueness of view names in the sheet where a view is created or renamed.

In drawing
Check the uniqueness of view names in the drawing.

By default, In sheet is selected.
 

Distinguish SBCS and DBCS characters
  This option is available for selection only when Ensure uniqueness of sheet names, Ensure uniqueness of view names, or both are selected.

Select this check box to distinguish between single byte character set, SBCS, and double byte character set, DBCS, formats for sheet names or view names during creation or renaming.
This means “Sheet.1” written in SBCS format is different from “S h e e t . 1” written in DBCS format.
  By default, this check box is cleared.
 

Distinguish lower case and upper case
  This option is available for selection only when Ensure uniqueness of sheet names, Ensure uniqueness of view names, or both are selected.

Select this check box to distinguish between lowercase and uppercase characters for sheet names or view names during creation or renaming.
This means “Sheet.1” is distinguished from “sheet.1”.
  By default, this check box is cleared.